topic Re: Find set datum tag - creo 4 in 3D Part & Assembly Design

Find set datum tag - creo 4

StephenW — Sat, 28 Mar 2020 13:05:57 GMT

I copied an existing drawing that already had an A and B datum that was defined in the drawing as "set datum tags". During the modeling, the attachment points (both shown dimensions in the drawing) were removed.

I go back to the drawing, I tried creating datums A and B as "set datum tags" and it tells me they already exist.

In the past, i have been successful finding stuff like this with the find tool. Not this time. I tried find in the drawing, every find option I could use. I tried in the model. No luck there.

Just to be clear, these are drawing created set datum tags using the "datum feature symbol" from within the drawing. Little red underline on the B datum means it's a duplicate name.

The question is, how do I find a missing "set datum tag" within the drawing. I use the term "set datum tag" specifically because that is what it is called and what the find tool found when I created another that it did find in the drawing.

Re: Find set datum tag - creo 4

StephenW — Fri, 29 May 2020 13:04:31 GMT

I ran in to this problem again. I'm perplexed.

Re: Find set datum tag - creo 4

StephenW — Fri, 29 May 2020 14:16:28 GMT

I decided that this problem is drawing specific. If I make a new drawing with the same model, the problem doesn't exist. I also found that this drawing was copied but with a new and different model and the drawing had the same problem.

Re: Find set datum tag - creo 4

jbush — Wed, 11 Nov 2020 03:48:29 GMT

Same problem here in Creo 4.

Looks like it's a bug: https://www.ptc.com/en/support/article/CS304721

Re: Find set datum tag - creo 4

StephenW — Wed, 24 May 2023 12:45:46 GMT

https://community.ptc.com/t5/3D-Part-Assembly-Design/Datum-Feature-Symbol-quot-Duplicate-Label-quot-of-Deleted-Symbol/td-p/758134?source=ArticleViewerRelated

The answer was in this post

https://www.ptc.com/en/support/article/CS324109?_gl=1*3mjv2y*_ga*MTYyNzY4Mjk4LjE2ODQ5MjM3MDI.*_ga_1QBT6P6HR1*MTY4NDkzMTQxMy4zLjEuMTY4NDkzMjI0NS4wLjAuMA..&source=copyurl

Users can repair the data in Creo Parametric 4.0 M150, 6.0.5.0, 7.0.2.0 and 8.0.0.0 by setting the dtl option update_drawing to 10097712:

File > Prepare > Drawing Properties > click Change next to Detail Options
Set Option to: update_drawing
- Both the Option and Value must be entered manually (because this is a hidden option) for Add / Change to become available
Set Value to: 10097712
Click Add / Change > OK
Then Review tab > Update Sheets

How to set detail options: CS137953
About hidden detail options: CS31562

Fix for earlier datecodes and releases (including Creo 5.0):

Create a new drawing
Import the affected drawing into the new drawing with Layout tab > Import Drawing/Data
Save a copy of the drawing detail options from the old drawing and import them to the new drawing
Recreate missing annotations and compare drawings for any changes that might have occurred in the copying process, like bug fixes or missing entities

Re: Find set datum tag - creo 4

j_k — Wed, 18 Mar 2026 17:54:11 GMT

I get this error in the Annotate tab of the model... how do you fix it there? I do have a drawing as well, but I added the datum tag in the model.