topic Re: Editing Dimensions after placement problems in 3D Part & Assembly Design

Editing Dimensions after placement problems

leegardner — Fri, 31 Jan 2020 03:25:34 GMT

Hi There,

I am having a problem with Creo 5.0. Its possibly something im doing.

Lets say I have a simple part drawing, with a few dimensions created using the dimensions tool on the annotate tab. I create a hole diameter measurement and add some text through the dimension text box. All is well in the world. Close the drawing. Check in to Windchill or sometimes don't check in.

When I come back to the drawing later, say I want to change the text or add the basic box around the dimension/add a tolerance, when I select the dimension, Creo doesn't bring up the dimensions tab, instead it brings up a format tab. This gives me no options to make the changes I wanted to make. I have tried multiple different way of selecting the dimension, including ensuring that I am in the annotation tab and that I use the drop down selection filter. Nothing works.

The end result is that I have to delete the dimension and recreate it. Which is fine once or twice but when its every dimension on the drawing, then it becomes painful.

Any thoughts

Lee

Re: Editing Dimensions after placement problems

Dale_Rosema — Fri, 31 Jan 2020 12:46:15 GMT

Any pictures or screen shots you can share to clarify what you are asking?

Re: Editing Dimensions after placement problems

StephenW — Fri, 31 Jan 2020 13:13:19 GMT

Verify the .prt (or .asm) file is unlocked in windchill. Depending on your config file, created dimensions in the drawing may be actaully in the model. If the model is locked, you will not be able to edit the dimensions.

Re: Editing Dimensions after placement problems

MartinHanak — Fri, 31 Jan 2020 18:13:41 GMT

Hi,

please attach pictures of Creo UI. Show us

1.] which tabs are available when you create new dimension

2.] which tabs are available when you edit existing dimension

Re: Editing Dimensions after placement problems

leegardner — Sun, 02 Feb 2020 22:19:03 GMT

Hi Steve,

I think you are correct, I have just tried a few times and it wont let me edit a dimension in the drawing unless the model is also checked out, once its checked out it works fine. I wasn't aware of that.

Thanks

Re: Editing Dimensions after placement problems

StephenW — Mon, 03 Feb 2020 14:48:08 GMT

Just for clarification, there is a config option called create_drawing_dims_only and its default is NO which basically means that created dimensions in the drawing actually "belong" to the model and are stored in the model.

If you set the option to YES, then the created dimension is in the drawing only.

There are some drawbacks to each setting. One of which you found. I know another that affected us was if you had a created dimension, you couldn't associated model GD&T to the created dimension.

I think there are other advantages/disadvantages but I can't think of them right off hand