topic Re: Create a BOM index between Simplified reps in 3D Part & Assembly Design

Create a BOM index between Simplified reps

cschmid — Fri, 07 Dec 2018 13:44:40 GMT

Hello,

My company is trying to create drawings that are easier for our assembly line to understand. This means creating a drawing more like a step by step instructions. This means breaking up the complicated assembly into separate stages and we are doing this by creating simplified reps for each stage of assembly. However, we need an easy way to assign BOM balloons to each of the simplified rep views. Currently we assign a separate BOM table to each view and fix the index numbers to the same index number in the master rep BOM. This is very time consuming and there is a risk of mistakes.

I had two ideas as a solution, but I cannot get either to work.

Idea 1: Create BOM table with multiple &rpt.qty columns with each column assigned to a different stage. This works well because it shows all of the stages and the quantity of pieces at each, however, we cannot attach BOM balloons to any views because of the following error: "BOM Balloons are not supported for regions with multiple models."

Idea 2: Create a component parameter for each component in the assembly and call out this parameter in a custom balloon in each of the simp rep boms. I have been able to do this, but it seems very time consuming still because I have to individually create the parameter with each component. Is there a way that I can create a component parameter for all of my components and the then edit the parameter in the model tree.

Can someone help me find a work around?

Re: Create a BOM index between Simplified reps

Chris3 — Fri, 27 Oct 2017 02:22:12 GMT

First, if you haven't already, I would suggest you upvote this idea: Allow BOM Ballons from Master Rep Repeat Region to be displayed on Simplified Reps

We have solved this problem a couple of ways. One is what you mentioned - fixing the index on multiple regions.

The second is to change your balloons to be custom balloons. We have balloons that instead of calling out the find number call out the actual part number.

The third solution is to exploit a big in Creo that has been around for multiple releases. Hopefully they don't fix this, but no guarantees going forward. Creo won't let you move a balloon from a master rep view to a simplified rep view using the move item to view command. It will give you the error you mentioned. However, if you right click and choose "Edit attachment" and the change the selection from change ref to same ref, it will move the balloon to a view with a different rep. It can be a little tricky. The way it works is if you hover over the same line, surface, etc that the balloon is currently pointing to on your master view then the balloon will jump and point to the same line, surface, etc on any over view.

You might also want to look into Pro/Process. Its called "Process Plan" or "Process Planning" now. It's a part of the Advanced Assembly Extension.

Re: Create a BOM index between Simplified reps

dgschaefer — Thu, 25 Jun 2015 12:46:24 GMT

As Christopher said, If you have Advanced Assembly, you want to look at the Process Planning functionality. It is made for this exact scenario and makes this quite easy.

I'd look at it first, if you have it it will save you a lot of effort.

Re: Create a BOM index between Simplified reps

hkenyon — Thu, 12 May 2016 10:46:49 GMT

Hi Cameron,

It's a year later but this might still help! I've struggled with this for a while now and I think I've figured out a workaround. We have the same problem about trying to break down our assembly drawings into stages for instructive purposes and simplified reps just don't have the right options. I've ended up creating layers and hiding in the view then saving status to do it. This will allow you to hide components without creating a simplified rep. You can also select entire groups and patterns to hide rather than having to select each individual component. The BOM balloons can then be created by view (and it will automatically exclude the parts that are hidden). I've so far found it hasn't caused any problems but it's still early days!

My solution is as follows:

In your assembly, instead of creating a simplified rep, create a new layer.
1. In layer tree, right click > new layer.
2. Include all components you will want to hide in this layer. At this point you can change the layer tree back to model tree to select things from there (including patterns and groups).
3. Click OK
Now open the corresponding drawing and place a view.
Select the Layer Tree window and ensure the view you have placed is selected. You can use the select tool in the layer tree as well.
Scroll down to the layer and right click > hide. This should hide the components you selected earlier in that view only.
Right click ‘Layers’ > Save status.
Now you can place your BOM table and create balloons by view. This should only create balloons on the visible components.

Hope that helps! Let me know if you find any issues as I've only just started using this method.

Cheers,

Hannah

Re: Create a BOM index between Simplified reps

tvasina-2 — Tue, 07 Mar 2017 10:36:58 GMT

Hello all, unfortunately the third solution does not already work. Seems that they have fixed the bug

Re: Create a BOM index between Simplified reps

Chris3 — Tue, 07 Mar 2017 12:15:01 GMT

What version and datecode of Creo are you using? I just tried this in Creo 4 and it still works. If they haven't fixed it in Creo 4 I find it hard to believe they fixed it somewhere else.

Re: Create a BOM index between Simplified reps

tvasina-2 — Tue, 07 Mar 2017 12:21:03 GMT

We are using Creo 2.0 M140

Re: Create a BOM index between Simplified reps

Chris3 — Tue, 07 Mar 2017 12:30:51 GMT

Definitely Possible. I have Creo 2 M150 and it works fine. As I mentioned in the first post, it can be tricky .... you have to move you mouse over the same line / surface that the leader is attached to in the master rep view. It can help to change the reference attachment in the master view to a line / surface that can be easily seen in the rep view prior to choosing the same ref option if you are still having trouble.

Re: Create a BOM index between Simplified reps

StephenW — Tue, 07 Mar 2017 12:31:43 GMT

Make sure you choose the "same ref" in the dialog box.

Re: Create a BOM index between Simplified reps

tvasina-2 — Tue, 07 Mar 2017 12:48:15 GMT

I just found out that it works only with using a line placement not a surface. Then it is possible to Edit Attachment in a new view again.

Thank you. Nice trick

Re: Create a BOM index between Simplified reps

Domen — Tue, 25 Jul 2017 08:50:14 GMT

I tested the Edit Attachment method in Creo 3.0 M130 and if works fine.

But guess what, the "bug" was fixed in Creo 4.0 M020, so it doesn`t work anymore.

Well done PTC, fixing bugs that shouldn`t be fixed.

Re: Create a BOM index between Simplified reps

Chris3 — Tue, 25 Jul 2017 12:49:37 GMT

I don't have M020 so I can't confirm, but I would be surprised if they fixed it. Are you sure you tried a case in which the same entity (line, surface, etc) is in the other view?

Re: Create a BOM index between Simplified reps

Domen — Tue, 25 Jul 2017 13:41:41 GMT

Yes, I did test it. In both Creo 3 and Creo 4.

You can see the video in the attachment.

Re: Create a BOM index between Simplified reps

Chris3 — Tue, 25 Jul 2017 14:07:40 GMT

OK. FYI I tested in Creo F000 and it still works there. It does appear to have been changed from your video. If that is the case then it was changed in M010 or M020.

Re: Create a BOM index between Simplified reps

Domen — Wed, 26 Jul 2017 06:15:00 GMT

I opened a Case on PTC.

So let`s wait and see what they come up with.

Re: Create a BOM index between Simplified reps

Domen — Thu, 03 Aug 2017 05:56:29 GMT

I got an answer from PTC:

"This was an intentional bug fix in Creo 3 M140 and Creo 4 M020. We do not allow the user to show the balloons on a view of a different simp rep."

I will try to convince them, that it was a very useful bug and they should return it.

Re: Create a BOM index between Simplified reps

dschenken — Thu, 03 Aug 2017 08:30:12 GMT

The only method for repeat regions I have found that is reliable is to create assembly-level component parameters. These are associated with the component, not the part or sub-assembly. As a result they are stable.

The down side is that at first it seems like some work, but the upsides include: there is never a 'fix region' problem; items that should not appear in the BOM can be easily filtered out by assigning a particular flag value or by not assigning the cparam at all.

An additional upside is that item numbers can be assigned before the drawing is made so there is no need to hold up an external ERP system for drawing release. If parts are replaced the cparam sticks with the component so the balloons stay the same, unless the user wants to assign a new item number to them.

Overall, my experience was that the upfront effort to establish the cparams more than made up for chasing seemingly random changes due to the way Repeat Regions automatically evaluate and they take less time to update than fix/unfix.

Since the cparams are fixed to the model, they are identical across simplified reps and will automatically reflect the correct callouts for the related rep. If one is clever an additional cparam for the assembly step can prevent the same component from being called out twice on a drawing. You need to create a repeat region for each simplified rep/assembly step. This can be more convenient on multi-sheet drawings as the region can be on the same sheet as the related views.

Re: Create a BOM index between Simplified reps

Domen — Mon, 07 Aug 2017 13:08:25 GMT

I agree with you: The method you described sounds like a lot of work, but is probably worth it.

Re: Create a BOM index between Simplified reps

Domen — Mon, 07 Aug 2017 13:14:33 GMT

Final answer from PTC:

It is not planned for Creo 5.0, but given the high number of votes, PM expects this to be implemented in future releases.

So I guess we will have to fina another workaround. Which probably does not exist.

Or use a method described in previous post, by dschenken.

Re: Create a BOM index between Simplified reps

Chris3 — Wed, 16 Aug 2017 13:45:56 GMT

It may not work for you, but we have changed our work intructions to allow not using Find Balloons all together. Instead we have balloons that just simply have the part numbers were the default find balloons are.